[abaqus inp 만들기 레벨1] 11. 출력할 결과 선택 (History output)

아바쿠스에서 결과 출력 방법은 두가지가 있습니다. 

Field output : 공간에 따른 데이터 f(x,y,z)
history output : 시간에 따른 데이터 f(t)

지난시간에 Field output 을 정의했습니다. 오늘은 history output 을 정의해봅시다. 

strain enery 를 선택하겠습니다. 코드는 아래와 같습니다. 

 

*Output, history
*Energy Output
ALLSE,

 

이어서 step을 닫아줍시다. step 이 하나인 경우 닫지 않아도 되지만, 여러개인 경우도 있으므로 항상 닫아주는 것이 좋습니다. 

*End Step

 

전체 코드는 아래와 같습니다. 

 

*****노드 생성************************************************************
*node
1,0,0,0
2,5,0,0
3,10,0,0
4,0,5,0
5,5,5,0
6,10,5,0
7,0,10,0
8,5,10,0
9,10,10,0
10,0,0,5
11,5,0,5
12,10,0,5
13,0,5,5
14,5,5,5
15,10,5,5
16,0,10,5
17,5,10,5
18,10,10,5
19,0,0,10
20,5,0,10
21,10,0,10
22,0,5,10
23,5,5,10
24,10,5,10
25,0,10,10
26,5,10,10
27,10,10,10
*****엘리먼트 생성************************************************************
*Element, type=C3D8R,ELSET=BODY1
1,1,2,5,4, 10,11,14,13
2,2,3,6,5, 11,12,15,14
3,4,5,8,7, 13,14,17,16
4,5,6,9,8, 14,15,18,17
5,10,11,14,13, 19,20,23,22
6,11,12,15,14, 20,21,24,23
7,13,14,17,16, 22,23,26,25
8,14,15,18,17, 23,24,27,26
*****물성 생성************************************************************
*Material, name=STEEL
*Elastic
2e11, 0.3
*****물성 부여************************************************************
*solid section, elset=BODY1, material=steel
*****하중 가할 면 생성************************************************************
*surface, name=my_surface, type=Element
5, S2
6, S2
7, S2
8, S2
*****스텝 생성************************************************************
*Step, name=Step-1
*Static
1., 1., 1e-05, 1.
*****하중 부여************************************************************
*Dsload
my_surface, P, 10.
*****경계조건 설정할 노드 생성************************************************************
*Nset, nset=my_node_set,generate
1,9,1
*****경계조건 설정************************************************************
*Boundary
my_node_set, 1
my_node_set, 2
my_node_set, 3
my_node_set, 4
my_node_set, 5
my_node_set, 6
*****Field output 설정************************************************************
*Output, field
*Node Output
U
*Element Output
E, S
*****History output 설정************************************************************
*Output, history
*Energy Output
ALLSE,
***step 닫기
*End Step